CNC Material Machinability Chart
Compare machinability ratings, recommended cutting speeds, and feed rates for common CNC materials. Covers aluminum alloys, carbon and alloy steels, stainless steels, titanium, and engineering plastics.
CNC Material Machinability Chart
| MATERIAL | GRADE / ALLOY | MACHINABILITY RATING (%) | CUTTING SPEED (SFM) | FEED RATE (IPR) | HARDNESS | COMMON USES |
| Aluminum | 6061-T6 | 270 | 600–1000 | 0.004–0.010 | 95 HB | General purpose, brackets, housings, fixtures |
| Aluminum | 7075-T6 | 240 | 500–900 | 0.004–0.008 | 150 HB | Aerospace structures, high-strength fittings |
| Aluminum | 2024-T3 | 220 | 500–800 | 0.004–0.008 | 120 HB | Aerospace skins, fatigue-critical parts |
| Aluminum | 6063-T5 | 280 | 600–1000 | 0.004–0.010 | 73 HB | Extrusions, architectural, heat sinks |
| Aluminum | 5052-H32 | 200 | 500–800 | 0.004–0.008 | 60 HB | Marine, sheet metal, fuel tanks |
| Aluminum | 2011-T3 | 310 | 700–1200 | 0.005–0.012 | 95 HB | Screw machine products, fittings |
| Aluminum | MIC-6 (Cast) | 250 | 500–900 | 0.004–0.008 | 65 HB | Tooling plates, fixtures, base plates |
| Steel | 1018 (Cold Rolled) | 78 | 200–350 | 0.005–0.012 | 126 HB | Shafts, pins, general structural |
| Steel | 1045 (Medium Carbon) | 64 | 180–300 | 0.004–0.010 | 179 HB | Gears, shafts, bolts, studs |
| Steel | 1215 (Free Machining) | 136 | 300–500 | 0.005–0.015 | 167 HB | Screw machine products, high-volume parts |
| Steel | 12L14 (Leaded) | 170 | 350–550 | 0.006–0.015 | 163 HB | Precision turned parts, bushings, fittings |
| Steel | 4140 (Pre-Hard) | 66 | 150–275 | 0.004–0.008 | 28–32 HRC | Tooling, fixtures, high-strength components |
| Steel | 4340 (Alloy) | 57 | 130–250 | 0.003–0.007 | 30–36 HRC | Landing gear, crankshafts, heavy-duty parts |
| Steel | 8620 (Case Hardening) | 66 | 175–300 | 0.004–0.010 | 149 HB | Gears, camshafts, case-hardened parts |
| Steel | A36 (Structural) | 72 | 180–325 | 0.005–0.012 | 119 HB | Structural plates, brackets, weldments |
| Steel | O1 Tool Steel | 45 | 100–200 | 0.003–0.006 | 58–62 HRC (HT) | Dies, punches, cutting tools |
| Stainless Steel | 303 | 78 | 200–350 | 0.004–0.010 | 170 HB | Free-machining fittings, shafts, valves |
| Stainless Steel | 304 | 45 | 120–250 | 0.003–0.008 | 201 HB | Food equipment, medical, general purpose |
| Stainless Steel | 316 | 36 | 100–220 | 0.003–0.007 | 217 HB | Marine, chemical processing, medical implants |
| Stainless Steel | 17-4 PH (H900) | 48 | 130–250 | 0.003–0.007 | 40 HRC | Aerospace, nuclear, high-strength valves |
| Stainless Steel | 416 | 110 | 250–400 | 0.005–0.012 | 262 HB | Free-machining, valve stems, fasteners |
| Stainless Steel | 440C | 28 | 80–175 | 0.002–0.006 | 56–58 HRC (HT) | Bearings, knife blades, surgical tools |
| Titanium | Ti-6Al-4V (Grade 5) | 22 | 60–120 | 0.003–0.006 | 36 HRC | Aerospace, medical implants, racing parts |
| Titanium | Grade 2 (CP) | 40 | 100–200 | 0.003–0.008 | 80 HRB | Chemical processing, marine, medical |
| Titanium | Grade 5 ELI | 20 | 50–110 | 0.002–0.005 | 36 HRC | Orthopedic implants, surgical devices |
| Titanium | Grade 23 (Ti-6Al-4V ELI) | 20 | 50–110 | 0.002–0.005 | 36 HRC | Biomedical implants, aerospace fasteners |
| Plastic | Delrin (Acetal/POM) | 350 | 500–1000 | 0.005–0.015 | R120 (Rockwell M) | Gears, bearings, bushings, insulators |
| Plastic | PEEK | 180 | 200–500 | 0.004–0.010 | R126 (Rockwell M) | Aerospace seals, medical, semiconductor |
| Plastic | Nylon 6/6 | 300 | 400–800 | 0.005–0.012 | R118 (Rockwell M) | Gears, rollers, bearings, wear pads |
| Plastic | UHMW-PE | 320 | 400–900 | 0.005–0.015 | R65 (Shore D) | Wear strips, conveyor guides, food handling |
| Plastic | Polycarbonate (PC) | 280 | 400–800 | 0.004–0.010 | R118 (Rockwell M) | Guards, lenses, transparent enclosures |
| Plastic | PTFE (Teflon) | 250 | 300–700 | 0.004–0.012 | R58 (Shore D) | Seals, gaskets, chemical-resistant parts |
Quick Answer: What Is the Machinability Rating of a Material?
Machinability rating is a relative percentage based on AISI 1212 free-machining steel, which is set at 100%. A higher rating means a material cuts more easily, with longer tool life and better surface finish. 6061-T6 aluminum rates about 270%, 304 stainless about 45% and Ti-6Al-4V titanium about 22%. The rating reflects tool wear, cutting forces and finish.
This chart lists machinability ratings, cutting speeds and feed rates for 32 common CNC materials with: grade or alloy, machinability rating (%), cutting speed in SFM, feed rate in IPR, hardness and typical uses. Search by material such as 6061 or 304, or filter by aluminum, steel, stainless, titanium and plastics.
Common materials: 6061-T6 aluminum → 270% rating, 600–1000 SFM | 304 stainless → 45% rating, 120–250 SFM | Ti-6Al-4V → 22% rating, 60–120 SFM | Delrin → 350% rating | RPM = SFM × 3.82 ÷ tool diameter (in).
Notes on This Chart
- Machinability ratings are relative to AISI 1212 free-machining steel (rated 100%). Higher = easier to machine.
- Cutting speeds (SFM) are for carbide tooling. HSS tools should run at approximately 50% of listed values.
- Feed rates (IPR) are starting recommendations for turning. Milling feed per tooth is typically 40-60% of IPR values.
- Actual speeds and feeds depend on machine rigidity, tool geometry, depth of cut, and coolant.
- Hardness values shown are for the condition specified. Heat treatment can significantly change machinability.
Need parts machined from these materials?
Upload your CAD file for an instant quote. Free DFM review included with every order.
Frequently Asked Questions
What does the machinability rating percentage mean?
The machinability rating is a relative measure of how easily a material can be machined compared with a reference material, typically AISI 1212 free-machining steel at 100%. Materials with ratings above 100% are generally easier to machine, while those below 100% are more difficult. The rating considers factors such as cutting forces, tool life, and achievable surface finish.
What is SFM and how do I use it?
SFM stands for Surface Feet per Minute and represents the cutting speed at the tool-material interface. To convert SFM to spindle RPM, use the formula: RPM = (SFM × 3.82) / tool diameter in inches. For example, at 800 SFM with a 0.5-inch end mill, the calculated spindle speed is approximately 6,112 RPM.
Why is stainless steel harder to machine than carbon steel?
Many stainless steel grades are more challenging to machine because they can work-harden during cutting and have relatively low thermal conductivity, which keeps more heat near the cutting zone. Some grades can also produce built-up edge and long, stringy chips. Sharp cutting tools, appropriate rake angles, consistent feed rates, and effective coolant help reduce these machining challenges.
What is IPR and how does it relate to IPM?
IPR stands for Inches Per Revolution, representing the distance the tool advances for each spindle revolution. IPM, or Inches Per Minute, represents the actual feed rate. For turning, IPM = IPR × RPM. For milling, feed rate is typically calculated using feed per tooth × number of flutes × RPM. IPR provides a useful way to compare recommended feed rates across different spindle speeds.
Can I machine titanium on a standard CNC mill?
Yes. Titanium can be machined on a standard CNC mill when the machine, tooling, workholding, and cutting parameters are properly selected. Titanium has low thermal conductivity, so heat can concentrate in the cutting zone. Typical strategies include lower cutting speeds, consistent chip loads, sharp carbide tooling, rigid setups, and effective coolant delivery. For many titanium applications, cutting speeds around 60–120 SFM may be used as a starting range, with final parameters adjusted for the specific alloy, tool, and machining operation.